Submachine definition in the machine schemas

Submachine is a list of parameters for the pair: <tool holder, workpiece holder>. This is especially topical for complex machines with multiple spindles, multiple places for the workpiece, etc.

• ToolNode is a common parent node for all tool holders that are actual for the sub-machine

• WrkNode is a common parent node for all workpiece holders that are actual for the sub-machine

• XAxisID, YAxisID, ZAxisID - the axes that are responsible for the motion along X,Y,Z.

• ToolAxisID - the ID of the turret axis if it exists.

• OriginG54BaseNode - the ID of the axis where the workpiece coordinate system (WCS) is attached

• OriginG54 - additional transformation for the WCS. For example it allows to overturn the Z-axis in the counter spindle

• ApproachRule, ReturnRule - the default rules that will be used to build the approaches or returns.
  
  If no one submachine is declared in the schema then any tool holder can be used with any workpiece holder. It's done for the compatibility with the schemas developed for the previous versions of SprutCAM X. For example for the MTM turn-milling machine with two turrets and two spindles it must be defined the next submachines:

1. <Upper turret, main spindle>

2. <Upper turret, counter spindle> if Upper turret is able to work with the counter spindle

3. <Lower turret, main spindle> if lower turret is able to work with the main spindle

4. <Lower turret, counter spindle>

5. <Main spindle, counter spindle> for the takeover from the main spindle to the counter spindle

6. <Counter spindle, main spindle> for the takeover from the counter spindle to the main spindle
   SprutCAM X does not allow to choose the tool holder in the operation if it can not be used with the current workpiece holder (corresponding submachine is absent). The examples of the submachines declaration can be watched in the schemas "Index G160" and "Hanwha 32" that are included into the standard package.

Move Part operations

1. Added separate group for the operations which can move the part using robot or swiss-type/lathe machine. It comprises Pick and Place, MTM Takeover, Bar feeding and Sub spindle working operations.
   

   

2. New Bar feeding operation
   Any machining on the swiss lathe starts from the bar feeding. So the bar feeding operation must be the first in the operation list for the swiss lathes. On Hanwha swiss lathes it generates G300.
   
   

3. New Sub spindle working operation makes possible:

   • to synchronize the main and counter spindles.

   • to take the part by the counter spindle for the further machining in both spindles

   • to move the part in the main(counter) spindle

4. New CL-data command for the spindles synchronization
   
   

5. New "Clamp" CL-data command

Clamp devices now can be associated with the workpiece holders used by move part operations.

The new group of parameters is located on the "Strategy" inspector tab of the "Move part" operations. When the part is moved from one workpiece holder to another using the Takeover: command, the clamps which hold the part will automatically release/grip the part. Clamp devices can be added manually using vice/clamp fixtures or defined in the machine schema. Each device has an ID, clamps with the same ID are moved simultaneously. The CL-data command consists of device ID, and boolean flag to switch on/off the clamp device.

See the Clamp devices control documentation for more info.

Automatic reordering of the operations list for the machine schemas based on the swiss template

Automatic insertion of the channels sync points

Improved MTM takeover operation can be synchronized with the part-off operation.

1. Example schema “Hanwha 32” and project “Hanwha.stc” are included into the standard package.

2. Simulation in the multichannel mode is NOT fully debugged (expected in the release)

3. Example postprocessor for the Hanwha swiss lathe will be included into the package later.

The example of project is included into the standard package (project name "U-axis turning.stc"). The turning axis always is going through the workpiece zero (G54-G59). Define the correct Origin (G54-G59) and B-axis position before create the lathe operation. SprutCAM calculates the generatrix, based on the defined axis, and draw the solid of revolution.

Generated CLData will contain the command to switch the interpolation axes X/U. This command must be analyzed in the postprocessor. Tool tip point also depends on this mode.

New group of Probing tools added: one tool for the axial case (tooling point at the axis) another for the turn case (tooling points can be at side).

Due to the fact that there is no single standard for measuring cycles, a mechanism has been created that allows you to create your own set of cycles with a specific set of parameters needed for exact measuring equipment and CNC. So you can design your own cycle with only needed parameters and save it as template. Then you can place all created templates in a separate file with *.scpbl extension - a library of probing cycles - and transfer it to another computer along with the postprocessor and machine files. The " Design a new cycle " menu and properties customization button become available only when the option Show expert tools in the system settings window is enabled.

All custom cycle parameters are available in postprocessors using a syntax specially created for this case (you can see an example of probing cycles inside standard Fanuc (30i)_Mill_DN.dll postprocessor).

See Probing chapter for details.

Effector On/Off command

It is set if the simulation type is additive or paint according to the selected Effective Feeds. For additive operations and welding, the command is set to automatic.